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Hole Construction |
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In KOMPAS-3D, the following can be constructed:
•Hole with countersink and counterbore,
To construct a hole, you can use a flat object or a surface of any shape. To create the hole, its position and parameters must be specified. Position of the hole is determined by the position of its base point.
Base point is a point on the specified surface for construction, where the surface intersects with the hole axis.
In the hole you can create a centerline and/or thread (for some holes from the library the thread is not created).
In the Design Tree the hole is displayed with an icon according to its type. If the hole was created with a centerline and/or thread, then the axis icon and/or cosmetic thread icon is displayed in the Design Tree as a subordinate object of the hole. For thread, its designation is specified.
See Also
A simple hole is built using the Simple hole 
command.
Step-by-step instructions
1.Specify the plane or face to create the hole and set the position of its base point. More details on hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
2.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•Depth holes.
3.If necessary, specify the hole bottom shapeIn the group of elements Bottom.
4.If you work with a model that contains multiple solids and/or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the area of application...
5.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about selecting a coordinate system...
6.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the management of color and optical properties...
7.Click Create item 
button to complete the construction.
8.To complete operation of the command, click Finish 
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A hole processed by countersinking is plotted using the Hole with countersink 
command.
Step-by-step instructions
1.Specify the plane or face to create the hole and set the position of its base point. More details on hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
2.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•Depth holes.
3.In the Countersink control group, select the method to determine the countersink parameters by pressing the corresponding button in the Method group, and set these parameters (see the table).
Methods for defining countersink parameters
Method |
Rules for plotting |
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By diameter and angle |
The countersink surface is determined by the countersink diameter and the countersink cone angle. Specify the countersink diameter in the Diameter field and select the countersink cone angle from the Angle list. |
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By depth and angle |
The countersink surface is determined by the countersink depth and the countersink cone angle. Specify the countersink depth in the Depth field and select the countersink cone angle from the Angle list. |
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By diameter and depth |
The countersink surface is determined by the countersink diameter and the countersink depth. Specify the countersink diameter in the Diameter field and the countersink depth in the Depth field. |
4.If necessary, specify the hole bottom shapeHoles in the group of elements Bottom.
5.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details on the application area...
6.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
7.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More about the control of the color and optical properties...
8.Click the Create Object button to complete the construction.
9.To complete operation of the command, click Finish .
The hole, processed with a countersink, is created using the Countersink Hole 
command.
Step-by-step instructions
1.Specify the plane or face to construct the hole and set the position of its base point. More details on hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
2.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•For Depth holes.
3.In the Counterbore control group, specify:
•the counterbore diameter in the Diameter field,
•the counterbore depth in the Depth field.
4.If necessary, specify the hole bottom shapeholes in the group of elements Bottom.
5.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
6.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
7.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details about managing the color and optical properties...
8.Click Create Object button to complete the construction.
9.To complete operation of the command, click Finish .
Hole with countersink and counterbore
A hole processed with countersinking and counterboring is created using the Hole with countersinking and counterboring 
command.
Step-by-step instructions
1.Specify a plane or face to create the hole and set the position of its base point. More details on hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
2.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•Depth holes.
3.In the Countersink/Counterbore control group, specify:
•the total countersink/counterbore diameter in the Diameter field,
•the counterbore depth in the Depth field,
•the countersink cone angle in the Angle field.
4.If necessary, specify the Hole bottom shapeHoles in the group of elements Bottom.
5.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. Details about the application area...
6.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
7.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on managing the color and optical properties...
8.Click Create item button to complete construction.
9.To complete operation of the command, click Finish .
The conical-shaped hole is constructed using the Hole conical 
command.
Step-by-step instructions
1.Specify the plane or face to construct the hole and set the position of its base point. More details on hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
2.In the Hole control group, specify:
•the hole diameter (the diameter of the lower base of the cone) in the field Diameter,
•Depth holes.
3.Specify the method for defining conical hole parameters. With each method, the conical hole shape is achieved by increasing the diameter of the upper base of the cone. The upper base of the cone is a base that belongs to the surface where the hole is located. Click the desired button in the Method group and specify the parameters (see the table).
Methods for defining conical hole parameters
Method |
Rules for plotting |
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By upper cone base diameter |
The hole surface is determined by the diameter of the upper cone base. Specify the upper cone base diameter in the Base diameter field. |
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By cone angle |
The hole surface is determined by the cone angle. Specify the cone angle in the Cone angle field. |
4.If necessary, specify the hole bottom shapeHoles in the group of elements Bottom.
5.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
6.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
7.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the control of the color and optical properties...
8.Click the Create Object button to complete the construction.
9.To complete operation of the command, click Finish .
The shape of a hole from the library is defined by a parametric fragment from the element library. The library and the fragment from it are specified during construction of the hole. By default, used is the KOMPAS-3D library Hole.kle included in the supply package. More about the Libraries of Elements...
A hole from the library is constructed using the A hole from the library command 
.
Step-by-step instructions
1.Specify the plane or face where the hole will be located and set the position of its base point. More details about hole placement...
A phantom of the hole is displayed in the graphics area.
To set the hole parameters, you use controls located in the Main section of the Parameter Toolbar.
The file name of the current library and the path to it are displayed in the Library field.
2.Set the shape of the hole in one of the following ways:
•Click the Select the hole type from library 
button to the right of the field Form to invoke Hole selection dialog. In the left part of the dialog the list of holes in the current library is displayed. The right part shows the sketch of the specified hole profile and dimensions controlling the profile parameters. Specify the desired hole and click the Select button.
•Select the hole from the list in the Shape field.
Dimensions corresponding to the selected hole are displayed in the hole parameters table in the Hole group of the Parameter Panel.
3.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•Depth holes,
•the values of desired parameters in the hole parameters table.
After entering the new value in the hole parameters table in the Changed column opposite its name, a "checkmark" appears. Clicking the checkmark returns the original value of the parameter.
4.If you work with a model that contains multiple solids and/or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
5.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
6.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the control of color and optical properties...
7.Click the Create Object button to complete the construction.
8.To complete operation of the command, click Finish .
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To connect a new library, click the field name. The "Open File" dialog box will appear on the screen. The Library. |
•You can set the hole position in the graphic area using the characteristic points (see Section Defining Points of Objects).
•You can use the geometrical calculator.
•You can assign tolerances to the values of the operation parameters expressed in linear and angular values. To do this, call the Tolerance command located in the menu of the required parameter, or click the 
icon displayed in the parameter field (the icon is displayed if a tolerance is assigned to the parameter value). More details on assigning tolerance...
