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Hole construction |
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In KOMPAS-3D, the following can be constructed:
•Hole with countersink and counterbore,
Holes can be positioned in two ways:
1.Method: By surface parameters 
allows you to create a hole by specifying its position on a plane or surface of any shape.
2.Method: By points on surface 
allows you to create one or more holes based on points or objects containing points (for example, several points in a sketch, an array of points, etc.).
The location of the holes is determined by the position of their reference points.
•Base point of the hole during placement By surface parameters — this is a point on the surface specified for construction where the surface intersects the hole axis.
•Reference points for hole placement By points on surface are the point objects specified for the construction.
In the hole you can create a centerline and/or thread (for some holes from the library the thread is not created).
In the Design Tree, a hole is represented by an icon corresponding to its type. If the hole was created with an axis and/or a thread, the axis icon and/or the thread symbol are displayed in the Design Tree as child objects of the hole. For threads, the thread designation is specified.
If the construction results in multiple holes, their number is displayed in parentheses after the hole name in the Design Tree. The number of holes is determined by the number of points at which the generated holes intersect model objects in the specified direction. The remaining points are ignored. Consequently, the number of holes in the Design Tree may be fewer than the number of points selected for construction.
See also
A simple hole is built using the Simple hole
command.
Step-by-step instructions
1.Select the placement method for the hole(s) and specify the objects that determine the placement:
•For the By surface parameters method select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. Learn more about placement...
•For the method By points on surface Specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. Learn more about placement...
Placeholders for the hole(s) are displayed in the graphics area.
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The absence of a phantom indicates that it is impossible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set the hole parameters.
2.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•depth holes.
3.If necessary, specify the hole bottom shape in the group of elements Bottom.
4.If you work with a model that contains multiple solids and/or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the area of application...
2.You can select the coordinate system relative to which the hole will be positioned—the coordinates of its base point will be defined in the selected coordinate system. To do this, use the Coordinate System section. Learn more about selecting a coordinate system...
3.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the management of color and optical properties...
4.Click Create object 
button to complete the construction.
5.To finish the task, click the Finish 
button.
A hole processed by countersinking is plotted using the Hole with countersink 
.
Procedure
1.Select the placement method for the hole(s) and specify the objects that determine the placement:
•For the method By surface parameters select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. Learn more about placement...
•For the method By points on surface Specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. More about placement...
Placeholders for the hole(s) are displayed in the graphics area.
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The absence of a phantom indicates that it is not possible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set hole parameters.
2.In the Hole group, set the following:
•hole diameter in the Diameter field;
•the depth of the hole.
3.In the Countersink group, select the method for determining the countersink parameters by clicking the corresponding button in the Method group, and then specify these parameters (see table).
Methods for determining countersink parameters
Method |
Construction Rules |
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By diameter and angle |
The countersink surface is determined by the countersink diameter and the countersink cone angle. Specify the countersink diameter in the Diameter field and select the countersink cone angle from the Angle list.. |
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By depth and angle |
The countersink surface is determined by the countersink depth and the countersink cone angle. Specify the countersink depth in the Depth field and select the countersink cone angle from the Angle list. |
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By diameter and depth |
The countersink surface is determined by the countersink diameter and the countersink depth. Specify the countersink diameter in the Diameter field and the countersink depth in the Depth field. |
4.If necessary, specify the hole bottom shape holes in the group of elements Bottom.
5.If you work with a model that contains multiple solids and/or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the area of application...
5.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
6.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More about the control of the color and optical properties...
7.Click the Create Objectbutton to finish the construction.
8.To complete operation of the command, click Finish .
The hole, processed with a countersink, is created using the Countersink Hole 
command.
Step-by-step instructions
1.Specify the plane or face to construct the hole and set the position of its base point.
•For the method By surface parameters Select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. More about placement...
•For the method By points on surface Specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. Learn more about placement...
Placeholders for the hole(s) are displayed in the graphics area.
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The absence of a phantom indicates that it is impossible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set hole parameters.
2.In the Hole group, set the following:
•the diameter of the hole in the Diameter field;
•the depth of the hole.
3.In the Counterbore control group, specify:
•the counterbore diameter in the Diameter field,
•the counterbore depth in the Depth field.
4.If necessary, specify the hole bottom shapeholes in the group of elements Bottom.
5.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
5.You can select the coordinate system relative to which the hole will be positioned—the coordinates of its base point will be defined in the selected coordinate system. To do this, use the Coordinate System section. Learn more about selecting a coordinate system...
6.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details about managing the color and optical properties...
6.Click Create Object button to complete the construction.
7.To complete operation of the command, click Finish .
Hole with countersink and counterbore
A hole processed with countersinking and counterboring is created using the Hole with countersinking and counterboring 
command.
Step-by-step instructions
1.Select the placement method for the hole(s) and specify the objects that determine the placement:
•For the By Surface Parametersmethod select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. Learn more about placement...
•For the By Points on the Surface method specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. Learn more about placement...
Placeholder holes are displayed in the graphics area.
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The absence of a phantom indicates that it is impossible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set hole parameters.
2.In the Hole group, set the following:
•the diameter of the hole in the Diameter field;
•the depth of the hole.
3.In the Countersink/Conterbore element group, set the following:
•the total diameter of the reaming/countersinking in the Diameter field;
•the drawing depth in the Depth field;
•the angle of the countersink cone in the Angle field.
4.If necessary, specify the shape of the bottom of the hole in the Bottom group.
4.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. Details about the application area...
5.You can select the coordinate system relative to which the hole will be positioned—the coordinates of its base point will be defined in the selected coordinate system. To do this, use the Coordinate System section. Learn more about selecting a coordinate system...
6.You can select a coordinate system to place the hole relative to. To do that, use the Coordinate System section. More information about choosing a coordinate system...
7.Click Create object , button to complete construction.
8.To complete operation of the command, click Finish .
The conical-shaped hole is constructed using the Hole conical 
command.
Step-by-step instructions
1.Select the placement method for the hole(s) and specify the objects that determine the placement:
•For the By Surface Parameters method Select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. Learn more about placement...
•For the By points on the surface method specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. Learn more about placement...
Placeholders for the hole(s) are displayed in the graphics area.
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The absence of a phantom indicates that it is impossible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set hole parameters.
2.In the Hole group, set the following.
•hole diameter (diameter of the bottom of the cone) in the Diameter field;
•the depth of the hole.
3.Specify the method for defining the parameters of a tapered hole. In each method, the tapered shape of the hole is achieved by increasing the diameter of the upper base of the cone. The upper base of the cone is defined as the base belonging to the surface on which the hole is located. Click the appropriate button in the Method group and specify the parameters (see table).
Methods for determining the parameters of a tapered hole
Method |
Construction Rules |
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By upper cone base diameter |
The surface area of the hole is determined by the diameter of the top base of the cone. Enter the diameter of the top base of the cone in the Base Diameter field. |
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By cone angle |
The surface of the hole is determined by the cone angle. Set the cone angle in the Cone Angle field. |
4.If necessary, specify the shape of the bottom of the hole in the Bottom group.
4.If you work with a model that contains multiple solids and / or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
5.You can select the coordinate system relative to which the hole will be positioned—the coordinates of its base point will be defined in the selected coordinate system. To do this, use the Coordinate System section. Learn more about selecting a coordinate system...
5.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the control of the color and optical properties...
6.Click the Create Object button to complete the construction.
7.To complete operation of the command, click Finish .
The shape of a hole from the library is defined by a parametric fragment from the element library. The library and the fragment from it are specified during construction of the hole. By default, used is the KOMPAS-3D library Hole.kle included in the supply package. More about the Libraries of Elements...
A hole from the library is constructed using the A hole from the library 
command.
Step-by-step instructions
1.Select the placement method for the hole(s) and specify the objects that determine the placement:
•For the By surface parametersmethod select a plane or face for creating the hole, and specify the position of its base point. If necessary, specify the direction in which the hole should be created. Learn more about placement...
•For the By points on the surfacemethod. Specify points or objects containing points. If necessary, refine or specify the direction for creating the holes. Learn more about placement...
Placeholders for the hole(s) are displayed in the graphics area.
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The absence of a phantom indicates that it is impossible to create a hole based on the current input data and/or parameters. |
The controls located in the Main section of the Parameters Panel are used to set hole parameters.
The name and path of the current library are displayed in the Library field.
2.Specify the shape of the hole using one of the following methods:
•Click the Select the hole type from library 
to the right of the field form to invoke Hole selection dialog. In the left part of the dialog the list of holes in the current library is displayed. The right part shows the sketch of the specified hole profile and dimensions controlling the profile parameters. Specify the desired hole and click the Select button.
•Select the hole from the list in the Shape field.
Dimensions corresponding to the selected hole are displayed in the hole parameters table in the Hole group of the Parameter Panel.
3.In the Hole control group, specify:
•the hole diameter in the Diameter field,
•Depth holes,
•the values of desired parameters in the hole parameters table.
After entering the new value in the hole parameters table in the Changed column opposite its name, a «checkmark» appears. Clicking the checkmark returns the original value of the parameter.
4.If you work with a model that contains multiple solids and/or components, you may need to specify the operation application area in the Application area section, specify the application area type and select the objects intersection with which will be considered during the construction. More details about the application area...
5.You can select the coordinate system relative to which the hole will be positioned—the coordinates of its base point will be defined in the selected coordinate system. To do this, use the Coordinate System section. Learn more about selecting a coordinate system...
4.If necessary, set the name of the hole and its surface displaying properties in the Properties sector. More details on the control of color and optical properties...
6.Click the Create Object button to complete the construction.
7.To complete operation of the command, click Finish .
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To add a new library, click on the field name. A standard file open dialog will appear on the screen. The Library field contains a list of all libraries that have been used. |
•You can set the hole position in the graphic area using the characteristic points (see Section Defining Points of Objects).
•You can use the geometric calculator to set linear and angular parameters.
•You can assign tolerances to the values of the operation parameters expressed in linear and angular values. To do this, call the Tolerance command located in the menu of the required parameter, or click the 
, icon displayed in the parameter field (the icon is displayed if a tolerance is assigned to the parameter value). More details on assigning tolerance...
