KOMPAS-3D v23

When inserting a component into a model, it is necessary to specify parameters that define its position. For this you should use controls in the Main section of the Parameter Panel.

The order of setting the parameters depends on how the component is placed:

By coordinates,

By couplings.

To select the desired method, click the appropriate button in the Placement Method group. The item set on the Parameter Panel will change.

By coordinates

When placing a component using the By Coordinates method, the Parameter Panel displays elements for setting the placement parameters, and in the graphic model area – a phantom of the component and the base element .

Step-by-step instructions

1.Set the position of the component. To do this, determine the position of its insertion point – the point that coincides with the origin of the current coordinate system of the component – using the elements of the Position section of the Parameter Panel.

You can set the position using the following methods.

•Manual indication in the model graphic area. The component insertion point can be specified arbitrarily or using a snap (for example, to the CS origin or to a vertex). To make a snap, move the cursor to the desired object and, when the icon of this object appears next to it, click the left mouse button.

•Entering coordinates in the Coordinates field.

•Plotting a point. To do this, click the Plot Point button next to the Coordinates field. The process of building a point will start. Select the build method and configure the required parameters. These parameters will determine the position of the component’s insertion point. Note that in this case, the point construction process is used only to determine the position of the insertion point. This does not create a new point.

The position of the insertion point, specified by any of the above methods, is fixed – icons appear in the coordinate field of this point . If you need to set other point coordinates or specify its new position manually, disable the fixation.

You can change the position of the insertion point by specifying a point or using the base element without disabling its fixation.

2.Set the orientation of the axes of the coordinate system of the component using the elements of the Orientation group of the Main section on the Parameter Panel.

You can set the orientation using the following methods:

Axes Direction,

Euler angles,

By object.

Select the desired method using the button group Orientation Method and set the parameters corresponding to the selected method. These actions are similar to those described in the section Orientation LCS.

3.If necessary, you can change the position of the component in the model by specifying a different coordinate system of the component or of the current model. For this purpose use the elements of the Coordinate System group.

Initially, the component is placed in the model as follows:

•the origin of the current coordinate system of the component coincides with the insertion point,

•The axes of the current coordinate system of the component are aligned with the axes of the current coordinate system of the model,

•The coordinates of the component insertion point and the Euler angles are determined relative to the current coordinate system of the model.

To select the coordinate systems of the component and/or the current model, use the Component CS and Current Document CS lists, respectively. The choice is possible if there are local coordinate systems in the component or the current model.

From the list Component CS, select the component coordinate system that will be aligned with the insertion point. The component will change its position.

From the Current Document CS list, select the coordinate system of the current model relative to which the position of the component will be defined. The "behavior" of the component will depend on the state of the Keep position option:

•if that option is disabled, then when the model coordinate system is selected, the position of the component in the model changes; the coordinates of the insertion point remain unchanged, but are measured in the selected coordinate system,

•if that option is enabled, selection of the coordinate system of the model does not change the position of the component in it; the coordinates of the component insertion point and Euler angles change (their values are determined relative to the selected coordinate system).

If necessary, you can create a local coordinate system in the component or in the current model without interrupting the component insertion process. For this, the Design LCS buttons are used, located next to the coordinate system selection lists.

After pressing the button, the subprocess of creating LCS starts. Specify LCS parameters and click the Create object button. The system will return to the component placement process. The new LCS will be added to the appropriate list and will be automatically selected.

Features of creating an LCS for a component/current model

•Creating an LCS for the current model — the name of the new LCS appears in the Current Document CS, and the LCS itself is added to the model. It becomes current.

•Creating LCS for a component:

•In the Component CS list, there will appear a line Modified. In this case the LCS is not added to the component model. It is stored inside the insertion process under the name Changed. When you press the Design LCS button again, it performs editing of the already created LCS instead of creating a new one.

•To set the snap point and the direction of the LCS axes, you can specify only objects of the component itself. Objects of the current model and of other components are not available for specifying.

Method of component positioning by matings

When placing a component using the By matings method, positioning mates are created in the model to define its position. These matings do not differ from the matings created by special commands. More details on positioning matings...

Setting mating parameters is possible only when the component fixation is disabled (the toggle switch Fix is set to position 0). In this case, the mating creation elements appear on the Parameters Panel, while the component phantom and the Source model window are displayed in the graphical area of the model.

If fixation is enabled, the Parameter Panel does not display elements to create matings. For more details on control of fixation...

Step-by-step instructions

1.Specify the mating objects of the current model and the component in the Design Tree or in the graphic area of the model (you can also specify the component object in the Source model window). The names of the objects will appear in the Assembly Object and Component object fields, respectively.

2.Select the type of positioning mating by clicking the desired button in the Mating Selection group (button availability depends on the objects selected for mating).

•If creating the mating does not require to specify additional parameters, the mating will be automatically created.

•If you need to set additional parameters of mating (for example, distance for mating At Distance), a subprocess of creating the selected type of mating will be initiated. Set mating parameters and click the Create object button. The system will return to the original process.

The names of all created mates are displayed as a list in the Matings field.

You can include matings in the calculation and exclude them from the calculation, enabling and disabling the options corresponding to them in the list. Enabling/disabling the option in the All row includes/excludes all created couplings in/from the calculation.

To change the options of a mating, select it in the list and click the Edit mating button. This will start the process of editing the mating, which is similar to mating creation.

To delete a mate, click the icon in the row of that mate, or select the row and press the Delete button.