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Converting objects to a part and a local part |
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Objects that are available in the model can be converted into a part, and when working with an assembly, into a local part as well.
Converting objects to a part means saving objects built in the model (part or assembly) to a new part file (*.m3d). If transformation is performed in an assembly, the resulting part is inserted into it as a component.
•When working with a part, the objects selected for transformation are transferred to a new part and remain unchanged in the original part.
•When working with an assembly, the objects selected for transformation can remain in the original assembly or removed from it at the user's choice.
Converting objects to a local part means converting objects built in the current assembly to a local part of the same assembly.
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Object transformation to a part or a local part cannot be undone. Also, after the transformation, it becomes impossible to cancel operations performed in the model before the conversion. |
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If the transformed assembly object is constructed using other objects of this assembly, then after transformation into a local part, an object Contextual Link is created in the assembly, which contains a reference to the geometric copies of the used objects. For more details on working with the objectContext link… |
How to transform objects to a part or a local part
To transform objects to a part or a local part, select the objects to be transformed, set transformation parameters, and complete the operation.
Conversion commands
•Transform into part
•Transform into local part
Object selection
Transformation to a part or a local part is possible only for objects built directly in the current model (for a local part, only in the current assembly) and of the following types:
•solids,
•surfaces,
•3D curves and points,
•local coordinate systems,
•auxiliary planes,
•auxiliary axes.
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If you want to transform an object constructed in a component, you should enter the editing mode for this component. |
You can select the desired objects before or after invoking the conversion command. In the first case, after selecting objects, you can run the transform command from the context menu of one of them.
You can specify objects in the Design Tree or in the model graphics area.
Selected objects are highlighted in the graphics area, and their names are added to the Objects field.
Designation and name of the part/local part
To specify the designation of the part/local part, place the cursor in the Designation field. A panel will appear on the screen containing the elements of the designation generation – the input fields for the designation parts and the button to insert the document code.
Generate the designation and press <Enter>.
Composition and step-by-step instructions to define the model designation
You can also select a designation from the external reference (ESKD Classifier) by clicking the Reference 
button next to the Designation field. The reference should be connected to KOMPAS-3D.
Enter the name of the part/local part in the Name field.
Part File Name and Location
When converting objects into a part, specify the name of the file where the created part will be stored and the path to it. Details...
If the objects are converted into a local part, you don’t need to specify the file parameters, since the local part is stored in the file of the model it is created in.
How to copy objects into a part or a local part
With the help of the Save design history toggle, determine the method for copying objects into a new part/local part.
By default, the toggle switch is set to position I (enabled). This means that the objects themselves, the sketches used in their construction, and the data about the remaining source objects will be transferred to the model. The data type depends on the type of the current model:
•if the transformation is performed in detail, then in the new model are created copies of the original objects' geometry,
•if the transformation is performed in an assembly, then the new model creates references to the assembly file, similar to those that are generated in the component file during its editing "in place", if this involves using objects of other assembly components.
When saving with history, all expressions specified for calculating parameters of the elements of the objects being converted, as well as all variables of the main section, are transferred to the model in addition to the source objects.
The position of objects is preserved when they are transferred to the model, i.e. the transferred objects will be located in the coordinate system of the new model in the same way as they are located in the coordinate system of the source model.
If you need to transfer only the objects to the model, without source objects and variables, set the Save design history toggle switch to position 0 (disabled). This will make the Mirror Part option appear on the Parameters panel. If you want the objects transferred to the new model to be mirrored relative to the XY plane, enable this option.
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If you obtain a solid using the Cut or Thicken, it is correctly transferred to the model only without saving construction history. If you save construction history, the created model will contain an error. |
Advanced options when working with an assembly
When working with an assembly, you can use the following additional object transformation options.
•Creation of a part/local part not as a component, but as detailing geometry. To do this, enable the Detailing Geometry option.
•Delete objects selected for transformation after creation of the component. To do this, use the Delete Original option. If this option is enabled, then after creating the component, the selected objects are deleted from the assembly. Note that only the objects selected for transformation are deleted. Their source objects remain unchanged. If this option is disabled, the selected objects are kept unchanged in the assembly.
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If the object selected for transformation participates in matings, then in the case the source is deleted, a new component will be involved in these matings, and if the source is preserved, the matings will not change. |
Completing the operation
To complete transforming the objects, click the corresponding button on the Parameter Toolbar header:
•when creating a part, the Save 
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•When creating a local part, the Create Object 
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The selected objects will be written to the part or the local part.
If the transformation was performed in the assembly, the assembly Design Tree will display a icon corresponding to the component type:
part,
local part.
See Also
General information about components
