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Cut Construction |
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To create an arbitrary cut in a sheet part, use the Cut in Sheet Solid command.
Step-by-step instructions
1.Specify the operation resultby clicking the necessary button in the Result group on the Parameter Panel:
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Subtraction,
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Intersection.
2.Set the cut sketch.
•If the model contains a sketch, you can use the whole sketch or its part — an area obtained by intersection of the sketch contours or restricted by one of them.
•To select a sketch, specify one of its objects in the graphic area of the model or specify the sketch itself in the Design Tree.
•To select an area in a sketch, click inside that area.
•If there is no required sketch, build one by clicking the Create Sketch button 
to the right of the Sketch field. The sketch placement process will start, and then the system will switch to the Sketch mode for creating geometry. Perform the steps necessary for building, then exit the sketch mode. The created sketch will be automatically selected.
After selecting a sketch, a phantom of the cut appears in the graphic area. The arrow on the phantom shows the construction direction.
The name of the selected sketch is displayed in the Sketch field. When you select a sketch area, the word Area is added to the field content.
You can change the sketch if necessary. To do this, click Sketch field and select the required sketch or sketch area. You can also edit the selected sketch by clicking the 
icon in the Sketch field.
3.Select the cut construction method by clicking the required button in the To face group:
By Thickness — if the cut includes a bend, the cut passes to it as a "wrapper"; the depth can be determined automatically or entered manually;
For Depth or 
For Depth — if the cut includes a bend, the cut does not pass to it as a "wrapper"; the depth can be specified by a number or by specifying a face.
More details on Construction Methods...
4.If required, enable the Perpendicular border option (available if the For Depth or For Depth buttons are pressed in the To face group). The state of this option determines the shape of the flange (side faces of the cut):
•when the option is enabled, the edge takes such a shape that it becomes perpendicular to the sheet plane after unbending the bend,
•when the option is disabled, the edge is trimmed by the surface generated by extrusion of the sketch in a direction perpendicular to its plane; such an edge is generally not perpendicular to the sheet plane after unbending the bend.
5.If required, set the name of the cut and properties of its surface display using the controls located in the Properties section.
More about managing the object color and optical properties...
6.To complete cut construction, click Create Object button 
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7.If the construction results in a solid consisting of multiple parts, then after completing the operation, the Modify Set of Parts process will start. Leave the parts which you need.
8.To complete operation of the command, click Finish 
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After completing the above steps, the cut will appear in the sheet part and its icon 
will appear in the Design Tree.
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The cut including a bend can be built so that changing the bend state becomes impossible. |
See Also
