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Adding imported components |
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Step-by-step instructions
1.Call the Add a component from a file 
command.
The standard file selection dialog or the Select a component source file (In the latter case, press the Choose from the disk... button to switch to the standard file selection dialog.)
2.In the file selection dialog, specify the format using the File Type list and choose the required file. The model will be read from the file. During the reading process, a progress toolbar is displayed on the screen showing the degree of its completion.
After reading is completed, a component phantom will appear in the model's graphic area, and elements of the insertion setup will appear on the Parameter Toolbar.
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You can select several models at once for insertion — their names will be added to the Parameter Panel list. Models from the list are inserted in sequence, with the insertion parameters set for each of them. For more details on inserting multiple components... |
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When inserting a SolidWorks model (*.sldprt, *.sldasm) containing configurations, only the current configuration is imported into the assembly. The component geometry and properties will correspond to this configuration. The list of all configurations will appear in the list Variation on the Parameters panel. You can select a different configuration by specifying it in the list, if needed. The selected configuration will also be imported into the assembly. Later, you can change the component model configuration. See section on changing configuration details... |
3.Setup component placement To do this, select the placement method and set the parameters corresponding to the selected method. These actions are performed using the controls from the Main section of the Parameter Toolbar.
To select a placement method, click the desired button in the Placement Method group:
By coordinates,
According to conjugations.
Set the placement parameters and check their correctness using the phantom.
Specifying parameters during coordinate placement...
Setting parameters when placing on conjugations...
4.Determine whether or not the component should retain a link to the source file. The Save connection switch is used for this in the Linked to the source section.
•For the component to be linked to the source file, set the Save connection switch to the I (on) position. In this case, the Follow the source option will be displayed on the Parameters panel.
Enable this option to receive information about changes in objects of the source model (changes are shown in the Design Tree with an icon 
next to the component name). Disable the option if you don't need to follow changes. For more details on change control...
The preservation of the link to the source file allows changes to the source model to be transmitted to the component. To do this, use the Update Imported Component 
command from the context menu of the component in the Design Tree. More details about component update...
•For the component not to be linked to the source, set the Save connection toggle switch to position 0 (disabled).
5.Fix the component or disable its fixation, if needed. To do this, set the Fix toggle switch in the Main section of the Parameter Panel into the desired position. For more details on the special features of fixing components...
6.To add a component to the BOM, enable the Include into BOM option in the Additional Parameters section. More details on creating a BOM based on data contained in the document...
7.You can convert the coordinate system of the component from right-side to left-side, if needed. To do this, enable the Invert Z Axis of CS option in the Additional parameters section. Details about Right-Side and Left-Side Coordinate Systems...
8.You can select the method of placing the component on the assembly layers. These elements are used for group Display in section Additional parameters. More information about methods of component placement on layers...
9.To complete insertion of the component, click the Create Object 
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An imported component will be created in the model. A component name taken from the source file and an icon will appear in the Design Tree:
imported component, linked with the source,
Imported component not linked to the source.
The created component is stored in the model as a local part.
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Please note that a component obtained from an interchange format file is a local part regardless if it retains the link with the source or not. |
If the placement method of the component is By matings, then the Mates section of the Tree displays the sequence of building the model. Positioning matings, created during the insertion of the component.
After the insertion is complete, the command does not finish working. This allows you to quickly insert several components into the model. The command saves the selection of the component source file and the configuration of additional parameters. You can create multiple inserts of the same model, or select a new source file for each insertion.
After adding all the necessary components to the model, complete the command by clicking the Finish 
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See Also
