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Performing the conversion |
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To build a sheet solid based on an existing model, use the Convert to Sheet Solid 
command.
Step-by-step instructions
1.Select a flat face of the source model. The name of the selected face will appear in the Base Face field on the Parameter Panel.
A phantom of the sheet solid will be displayed in the graphics area.
2.Specify material thickness and direction of adding material using the Thickness field and the Change direction button 
to the right of this field.
3.Specify bends in the sheet solid that you create. Details...
4.Define the parameters of the bend:
•In the list Length Determination Method, select a method for determining the flat pattern length: Coefficient, Bend amount, Bend Reduction, Bend table.
Specify the parameter for the selected method using the corresponding field in the Bend Parameters group.
•Select a method for setting the flanging Bend radius and set the value in the Radius field (for bends forming at the location of the specified linear edges).
The settings apply to all bends in the sheet solid. If required, you can set the parameters for each bend separately. Details...
5.Set parameters of capping adjacent corners between adjacent bends:
•specify a capping method Select the capping method by clicking the required button in the group Capping Method,
•specify a angle processing method, by clicking the required button in the Corner Treatment,
•enter a gap in the field Gap.
The corners for capping will be determined by the system automatically. The capping options apply to all corners. If required, you can configure the capping parameters separately for each corner. Details...
6.You can hide the original model or keep it visible using the option Delete source object.
•Enabling this option means that the source model will be hidden in the graphic area after the transformation is complete. You cannot enable its display in the graphic area. If the sheet solid is deleted, the source model will become visible again.
•Disabling the option means that the source model remains visible in the graphic area.
You can also hide the source model after the construction is complete (see Managing visibility of objects).
7.If required, set the name of the sheet solid and properties of its surface display using the controls located in the Properties section.
More about the control of the color and optical properties of objects...
8.To complete building, click Create object 
.
After confirming the completion of the operation, a sheet body will appear in the model, and in the Construction Tree, an operation transformation icon .
The resulting sheet solid is displayed in the Design Tree as a single object. You can add other sheet elements to the transformed sheet solid, also you can unbend and bend its bends.
9.To complete the command, click Finish 
.
Tips
•To set linear parameters of the operation, you can use commands of the geometrical calculator.
•You can set the thickness of a sheet solid, bend radius and some other parameters of a sheet solid in the graphics area using the defining points.
•You can change the default values of the sheet solid parameters in the Sheet solid properties.
•You can assign a tolerance to the operation parameters expressed in linear values. To do this, invoke the Tolerance command located in the desired parameter menu, or click the 
icon displayed in the parameter field (the icon is displayed if a tolerance is assigned to the parameter value).
More details on assigning tolerances...
See Also
